CNC मशीन मे Grooving Operation Programme केसे बनाये.

 

          CNC मशीन मे Grooving Operation क्या हे

Hello दोस्तो CNC मशीन मे Grooving एक ऐसा ऑपरेशन हे जो Shaft के उपर किया जाता हे क्योकि Shaft के उपर जब हम Bearing लगाते हे. तब हमारी Bearing निकल न जाये. इस लिये हम Circlip लगाते हे और Circlip लगाने के लिये हमको Grooving Operation करने की जरुरत होती हे.

Types Of Grooving Operation

1 Circlip Grooving / Simple Grooving

2 Profile Grooving

3 Thread Relive Groove

Example :-

Rpm Search : CS × 1000 / ∏ × D

            : 130 × 1000 / 3.14 × 30

            : 130000 / 97.2

            : 1380

O0001;

G00 G30 U0.0 W0.0 T0;

T0303;(3.0 mm Grooving Tool Insert Width)

G00 X32.0 Z5.0 M08;

G50S1380;

G96S130 M03;

G00 Z-13.0;

G01 X24.0 F0.07;

G04 X6; (Dwell Time)

G00 X32.0;

G00 Z5.0;

M05;

M09;

G00 G30 U0.0 W0.0;

M30;

Example :-

Rpm Search : CS × 1000 / ∏ × D

             : 130 × 1000 / 3.14 × 45

             : 130000 / 141.3

             : 920

 

 

O0002;

G00 G30 U0.0 W0.0 T0;

T0202;(3.0 mm Grooving Tool Insert)

G00 X47.0 Z5.0 M08;

G50S920;

G96S130 M03;

G00 Z-12.5;

G01 X41.0 F0.06;

G04 X6; (Dwell Time)

G00 X47.0;

G00 Z5.0;

M05;

M09;

G00 G30 U0.0 W0.0;

M30;

Example :-

Rpm Search : CS × 1000 / ∏ × D

              : 130 × 1000 / 3.14 × 60

              : 130000 / 188.4

              : 690

O0003;

G00 G30 U0.0 W0.0 T0;

T0505;(2.0 mm Width Ext.Grooving Tool)

G00 X62.0 Z5.0 M08;

G50S690;

G96S130 M03;

G00 Z-10.5;

G01 X52.0 F0.1;

G04 X6; (Dwell Time)

G00 X62.0;

G00 Z-12.5;

G00 X60.0; (Tool Touch)

G01 X52.0 Z-10.5;

G00 X62.0;

G00 Z-14.5;

G01 X60.0;(Tool Touch)

G01 X52.0 Z-10.5;

G00 X62.0;

G00 Z5.0;

M05;

M09;

G00 G30 U0.0 W0.0;

M30;

Example :-

Rpm Search : CS × 1000 / ∏ × D

             : 120 × 1000 / 3.14 × 40

             : 120000 / 125.6

             : 955

O0004;

G00 G30 U0.0 W0.0 T0;

T0606;(Ext.Grooving Tool)

G00 X42.0 Z5.0 M08;

G50S955;

G96S120 M03;

G00 Z-12.0;

G01 X33.0 F0.08;

G04 X6; (Dwell Time)

G00 X42.0;

G00 Z-11.0; (Chamfer)

G01 X40.0;(Tool Touch)

G01 X38.0 Z-12.0;

G00 X42.0;

G00 Z-14.0;(Tapper)

G01 X40.0;(Tool Touch)

G01 X33.0 Z-12.0;

G00 X42.0;

G00 Z-15.5;(Tapper)

G01 X40.0;(Tool Touch)

G01 X33.0 Z-12.0;

G00 X42.0;

G00 Z5.0;

M05;

M09;

G00 G30 U0.0 W0.0;

M30;

Example :-

Rpm Search : CS × 1000 / ∏ × D

             : 120 × 1000 / 3.14 × 50

             : 120000 / 157

             : 764

O0005;

G00 G30 U0.0 W0.0 T0;

T0303;(Ext.Grooving Tool)

G00 X52.0 Z5.0;

G50S764;

G96S120 M03;

G00 Z-17.5;

G01 X25.0 F0.1;

G04 X6;(Dwell Time)

G00 X52.0;

G00 Z-16.0;

G01 X25.0;

G04 X6;(Dwell Time)

G00 X52.0;

G00 Z-13.5;

G01 X50.0;

G01 X25.0 Z-16.0;

G00 X52.0;

G00 Z-11.0;

G01 X50.0;

G01 X25.0 Z-16.0;

G00 X52.0;

G00 Z5.0;

M05;

G00 G30 U0.0 W0.0;

M30;

Example :-

O0006;

G00 G30 U0.0 W0.0 T0;

T0606;(Ext Grooving)

G00 X42.0 Z5.0 M08;

G50S1433;

G96S180 M03;

G00 Z-13.0;

G01 X34.0 F0.1;

G04 X6;(Dwell Time)

G00 X42.0;

G00 Z-14.0;

G01 X40.0;

G01 X30.0 Z-13.0;(Chamfer)

G00 X42.0;

G00 Z-10.5;

G01 X34.0;

G04 X6;(Dwell Time)

G00 X42.0;

G00 Z-7.5;

G01 X40.0;

G01 X34.0 Z-10.5;

G00 X42.0;

G00 Z-7.5;

G01 X40.0;

G02 X34.0 Z-10.5 R3.0;

G00 X42.0;

G00 Z5.0;

M05;

M09;

G00 G30 U0.0 W0.0;

M30;

Example :

O0007;

G00 G30 U0.0 W0.0 T0;

T0606;(Ext.Grooving)

G00 X38.0 Z5.0 M08;

G50S170 M03;

G00 Z-9.5;

G01 X30.0 F0.1;

G04 X6; (Dwell Time)

G00 X38.0;

G00 Z-8.5;

G01 X36.0;

G01 X34.0 Z-9.5;(Chamfer)

G00 X38.0;

G00 Z-11.5;

G01 X30.0;

G04 X6;(Dwell Time)

G00 X38.0;

G00 Z-14.5;

G01 X36.0;

G01 X30.0 Z-11.5;     

G00 X38.0;

G00 Z-14.5;

G01 X36.0;

G03 X30.0 Z-11.5 R3.0;

G00 X38.0;

G00 Z5.0;

M05;

M09;

G00 G30 U0.0 W0.0;

M30;

                                      दोस्तो आपको Grooving के Operation के बारे मे पता चल गया होगा की Grooving के Operation का Programme केसे बनाते हे. तो दोस्तो आपको ऐ Post अच्छा लगा हो तो आप अपने Friends को SHARE जरुर करे. ताकि उस को भी हेल्प मिल सके.